/ANIM/BRICK/Restype
Engine Keyword Generates animation files containing brick element data for the specified result. Options used for BRICK element type.
Format
/ANIM/Eltyp/Restype
Definition
Field  Contents  SI Unit Example 

Eltyp  Element type.


Restype 

Comments
 For brick elements, the stresses are output in the elemental (corotational) coordinate system for /PROP/TYPE14 (SOLID) elements, and in the orthotropic material coordinate system for /PROP/TYPE6 (SOL_ORTH) elements, when corotational formulation is used. For all other cases the stresses are output in the global coordinate system.
 Using
/ANIM/BRICK/ORTHDIR with properties 6, 21, and 22 will output
3 real values of angle
$\psi ,\theta ,\text{and}\hspace{0.17em}\varphi $
in unit [deg]. Defining rotation matrix
$R$
, to go from global reference system to orthotropic
reference system:
 Rotation matrices
 A rotation of
$\psi $
radians about the xaxis is defined
as:
(1) $${R}_{x}\left(\psi \right)=\left[\begin{array}{ccc}1& 0& 0\\ 0& \text{cos}\psi & \text{sin}\psi \\ 0& \text{sin}\psi & \text{cos}\psi \end{array}\right]$$  Similarly, a rotation of
$\theta $
radians about the yaxis is defined
as:
(2) $${R}_{y}\left(\theta \right)=\left[\begin{array}{ccc}\text{cos}\theta & 0& \text{sin}\theta \\ 0& 1& 0\\ \text{sin}\theta & 0& \text{cos}\theta \end{array}\right]$$  Finally, a rotation of $\varphi $
radians about the zaxis is defined
as:
(3) $${R}_{z}\left(\varphi \right)=\left[\begin{array}{ccc}\text{cos}\varphi & \text{sin}\varphi & 0\\ \text{sin}\varphi & \text{cos}\varphi & 0\\ 0& 0& 1\end{array}\right]$$  The angles
$\psi ,\theta ,\text{and}\hspace{0.17em}\varphi $
are the Euler angles:
(4) $$R={R}_{z}\left(\varphi \right){R}_{y}\left(\theta \right){R}_{x}\left(\psi \right)$$(5) $$R=\left[\begin{array}{ccc}\text{cos}\theta \text{cos}\varphi & \text{sin}\psi \text{sin}\theta \text{cos}\varphi \text{cos}\psi \text{sin}\varphi & \text{cos}\psi \text{sin}\theta \text{cos}\varphi +\text{sin}\psi \text{sin}\varphi \\ \text{cos}\theta \text{sin}\varphi & \text{sin}\psi \text{sin}\theta \text{sin}\varphi +\text{cos}\psi \text{cos}\varphi & \text{cos}\psi \text{sin}\theta \text{sin}\varphi \text{sin}\psi \text{cos}\varphi \\ \text{sin}\theta & \text{sin}\psi \text{cos}\theta & \text{cos}\psi \text{cos}\theta \end{array}\right]$$
 The option SIGEQ is available with Eltyp = SHELL or BRICK only (/ANIM/SHELL/SIGEQ). Each material law, in Radioss has its own yield criterion to calculate the equivalent stress. For some it is von Mises; for others, it is Hill or Barlat or something else. For any nonvon Mises criterion, the corresponded equivalent stress (or criterion) is computed within all the integration points of the element. Therefore, the output field /ANIM/BRICK/SIGEQ is computed as a mean value over the all integration points.
 For brick elements, the stresses are output in the elemental (corotational) coordinate system for /PROP/SOLID elements, and in the orthotropic material coordinate system for /PROP/SOL_ORTH elements, when corotational formulation is used. For all other cases the stresses are output in the global coordinate system.
 The option /ANIM/ELEM/SIGX is only applied for shell elements. For brick elements, /ANIM/BRICK/TENS must be used.
 User variables
are only available for shell and brick elements. When an integration point is not
explicitly described, returned integration point means the integration point is
superior; computed as [(number of integration points in thickness + 1) / 2]. The
result is then rounded up to the superior value.
 Example:
For two integration points in thickness, second integration point from bottom (top of thickness) is returned.
For three integration points in thickness, second integration point from bottom (middle one) is returned.
For four integration points in thickness, third integration point from bottom is returned.
 Example:
 The Schlieren contour value is computed using $\xi ={e}^{c\nabla \rho}$ . Radioss outputs $\xi $ using c=1. The constant $c$ can be updated using HyperView by creating a derived result ${\xi}^{{c}_{user}}$ .
 For solid elements using
LAW51, it is possible to display results for a given submaterial number (1 to 4)
using:
 /ANIM/ELEM/LAW51/ALL: results for all submaterial, or
 /ANIM/ELEM/LAW51/1: results for submaterial 1
 /ANIM/ELEM/LAW51/2: results for submaterial 2
 /ANIM/ELEM/LAW51/3: results for submaterial 3
 /ANIM/ELEM/LAW51/4: results for submaterial 4
In this case, the following options can be displayed per phase: /ANIM/ELEM/P
 /ANIM/ELEM/DENS
 /ANIM/ELEM/ENER
 /ANIM/ELEM/SSP
 /ANIM/ELEM/EPSP
 /ANIM/ELEM/TEMP
 /ANIM/ELEM/VOLU
 /ANIM/MASS
 /ANIM/ELEM/LAW51/ALL: results for all submaterial, or
 For quad or brick elements, /ANIM/ELEM/DAM1, /DAM2, and /DAM3 are available for material LAW24. These values are the principal values of the damage (values in the local cracking skew).
 Element time step shows in animation only if elementary time step is computed for this element by Radioss. If nodal time step used (/DT/NODA) in computation, then no element time step shows in animation.
 Option
DAMG is only used with coupled damage models
(/MAT/LAW72 or /FAIL/GURSON) to output
damage over integration points. The damage variable is normalized by its
critical value.
 For /MAT/LAW72
(6) $${D}_{mg}=\frac{D}{{D}_{C}}$$  For /FAIL/GURSON
(7) $${D}_{mg}=\frac{{f}_{t}}{{f}_{F}}$$
 For /MAT/LAW72
 If /NONLOCAL/MAT option is activated, it is possible to output the regularized nonlocal plastic strain and its rate.