Load Step: Temperature

In the Temperature dialog, define and edit the *TEMPERATURE card.

To open the dialog in the Load Step window, select Temperature from the tree and a load collector from the Load collector table.

Load Step: Temperature: Define Tab

In the Define tab, define *TEMPERATURE cards on individual nodes or geometry (surfaces, points, lines). You can also define the temperature on node sets.

It is recommended that you do not use *TEMPERATURE and *BOUNDARY with dof 11 together in a load collector in =Engineering Solutions. If you need to use multiple types of temperature in the same STEP, define each type in a separate load collector and add them to the same load step.

You can define *TEMPERATURE on nodes, geometry, or node sets. For Define Temperature on:, the following options are available:
  • Nodes or geometry
  • Node sets

The layout of the Define tab changes, based on your selection.

Define Temperature On: Nodes or Geometry

Use the Define Temperature on: Nodes or geometry option to define temperature on individual nodes or geometry.

Temperatures created on nodes have special graphical display in Engineering Solutions. Loads created on geometric entities like surfaces, lines or points are automatically mapped to FEA mesh on export. You can also map them using the Map Loads on Geometry button.

The Define tab for Define Temperature on: Nodes or geometry contains the following buttons:
Table 1.
Button Action
Define from 'Forces'/'Moments' Panel Opens the Temperature panel to create/update temperature.

To create a temperature on nodes, go to the create subpanel, select nodes using the switch, input a value, and click create.

To create a temperature on geometry, go to the create subpanel, select surfs, points, or lines using the switch, input a value, and click create.
Note:
  • Loads created on geometric entities are automatically mapped to FEA mesh on export. You can also map them using the Map Loads on Geometry button.
  • You can also update an existing force or moments from the update subpanel.
  • While you are in the temperature panel, press the H key to view panel-specific help.
  • When you finish creating or updating temperature, click return to update the Step Manager with the new loads.
Map Loads on geometry Opens the Loads on Geom panel to map loads on geometry to FEA mesh entities.
Click Map loads to map all geometric loads in the current load collector to FEA entities.
Note:
  • You can also pick other load collectors by clicking on the loadcols button and map loads in all of them together.
  • While you are in the Loads on Geom panel, press the H key to view panel-specific help.
  • When you are finished, click return to update the Step Manager with the new loads.

Define Temperature On: Node Sets

The Define Temperature on: Node sets option defines temperature on node sets.

The node set names are used in the *TEMPERATURE data lines instead of the individual nodes. Unlike Abaqus surfaces in Engineering Solutions, you can combine node sets with individual node IDs in the same *TEMPERATURE card.
Note: There is no graphical display in Engineering Solutions for loads created on sets. Therefore, when you review a load collector in the Step Manager, only loads created on individual entities are highlighted. For loads defined on sets, the underlying nodes or elements are highlighted.
This dialog contains a node sets menu with a list of the existing node sets. It also contains a table for data line input with the following columns:
Table 2.
Column Description
Nset The name of the node sets. Node sets are added or removed using → or ←, respectively.
Temperature Reference temperature value.
Gradient1 Temperature gradient in the n2-direction for beams or temperature gradient through the thickness for shells.
Gradient2 Temperature gradient in the n1-direction for beams.
Load Id The ID of the load collector.

For tips on entering information and navigating in the Define tab, see Step Manager Tab Environment.

The Define tab for Define CLOAD-Force/Moment on: Node sets contains the following buttons:
Table 3.
Button Action
Review Set Reviews the selected node sets by highlighting them in the Engineering Solutions graphics. Right-click Review to clear the review selections.
Create/Edit Set.. Opens the Entity Sets panel in Engineering Solutions. When you finish creating/editing the set, click return. The Step Manager is updated with the new set appearing in the element set list.
Display/Review from panel Opens the appropriate Engineering Solutions panel. Use the review button to expand the loads and constraints on the sets for visualization purposes.
→ Add the selected node set from the drop-down menu to the data line table on the right.
← Delete the selected node set from the data line table.
Review/Reset Reviews the selected node set in the data line table. Right-click on Review to clear the highlighted selections.
Update Updates the Engineering Solutions database with the data lines defined in the table. By default, Engineering Solutions does not create a display for loads defined with sets.

For tips on entering information and navigating in the Define tab, see Step Manager Tab Environment.

Load Step: Temperature: Delete Tab

In the Delete tab, delete boundaries and other loads.

There are three deletion options:
Table 4.
Option Description
All loads in current collector The Delete button deletes all the loads from the current load collector.
All 'Temperature' in current collector The Delete button deletes only *TEMPETATURE loads from the current load collector.
By selection The Pick Loads button opens the Engineering Solutions load selector panel. Pick the loads you want to delete and click proceed.

The corresponding Reset button resets the selected loads.

The Delete button deletes the selected loads.

Load Step: Temperature: Parameter Tab

In the Parameter tab, define optional parameters for the *TEMPERATURE card.

The supported parameters include: Bstep, Binc, Estep, Einc, Input file, Result file, OP, and MidSide.

Click Update to activate the optional parameter selection in the database.